Unlock the Secrets of AP100 Programming and Typesetting Techniques | MachineMFG

Inquire About Our Sheet Metal Machines Now!

Unlock the Secrets of AP100 Programming and Typesetting Techniques


Are you struggling with programming and typesetting techniques for your hydraulic punch press? Look no further!

This comprehensive guide covers everything you need to know, from die shapes to die cutting quantity, length calculation, leaving nodes, and more. Whether you’re a beginner or an experienced operator, this article is packed with valuable tips and tricks to help you optimize your punch press operations and achieve better results.

So, buckle up and get ready to take your skills to the next level!


1. Familiarization with common and specialized die shapes:

Knowing the available dies makes programming more convenient and efficient.

2. Rational application of die clearances:

Previously, the standard clearances were 0.1 times the plate thickness for aluminum and copper, 0.15 times for iron, and 0.2 times for stainless steel. Now, AMADA proposes a new die clearance standard for hydraulic punch presses (all three of our factory’s presses are hydraulic).

The die clearance can be appropriately increased by 0.05 times the plate thickness based on the original standard.

This is because hydraulic punch presses have a slower instantaneous cutting speed, and increasing the die clearance will not affect the appearance of the cut section while preventing material from skipping during the cutting process.

3. Die cutting quantity:

During the cutting layout process, it is essential to calculate the cutting amount of each die strike. Generally, the length of material cut by the die should not be less than 2/3 of the die length; otherwise, there may be remnants left.

Rectangular shapes are prone to remnants, mainly at the four right angles, while circular shapes are the least likely to have remnants. Therefore, it is crucial to pay attention to the punching sequence during the cutting layout process.

In the example above, Figure 1 shows that punching the circular shape first and the square shape afterward can easily cause the four corners of the square shape to crack. If the punching sequence is changed to that in Figure 2, the wear on the die will be much less.

During the cutting layout process, it is essential to use the longer edge of the die for cutting the edges, as shown in the following example:

4. Length calculation in programming:

(1) On true line cutting:

When cutting edges continuously, the internal program of the machine itself will calculate this edge by dividing the total length of the cut edge minus the length of the first cut, rather than the total length divided by the blade length as we might imagine.

It is essential to note that when the punch press cuts edges continuously, it does not precisely connect each cut to the next. Instead, the punch press automatically defaults to a 0.2mm overlap between the two cuts. We must pay attention to this when calculating.

For example, when cutting a 240mm edge with an RE80x5 rectangular blade, we might think that precisely three cuts are needed.

However, if using on true line cutting, four cuts will be made in reality, which significantly affects die wear and service life.

There are two solutions to this: first, we can use a single-blade approach, cutting one at a time; second, based on the actual situation, we can leave a 0.4mm node on the first cut.

(2) Nibbling:

Not all round or square dies can be used for nibbling. In our factory, we use φ10, φ11, φ12 round dies and RE6x3 square dies for nibbling. It is better not to use other dies for nibbling, especially smaller ones. Nibbling is only suitable for thin plates, as it causes rapid wear on dies when used on thick plates.

When using a round die for nibbling a circle, first punch the center with a larger round die and then proceed with nibbling. Do not leave any nodes. When nibbling with a square die, it is best to leave three evenly spaced, smaller nodes along the circumference.

5. Leaving nodes

During the programming process, nodes should not be left too large or too small; also, they should not be left too many or too few. If the nodes are too large, the product will be difficult to remove or become deformed after removal. If the nodes are too small, the product may fall off.

What is the most appropriate size for nodes?

There is no definite standard; it depends on the actual situation. The ideal node size is one where the product will not fall off during the punching process and will detach from the material due to its weight when the operator pulls the sheet from the worktable.

Here are some reference values for your consideration:

Metals <1.0 1.0-1.6 1.6-2.5 2.5-3.0
Corner nodes Middle nodes Corner nodes Middle nodes Corner nodes Middle nodes Corner nodes Middle nodes
Aluminum, Copper 0.35 0.4 0.4 0.5 0.5 0.5 0.5 0.6
Iron 0.3 0.4 0.4 0.4 0.4 0.5 0.4 0.5
Stainless Steel 0.3 0.35 0.3 0.35 0.4 0.4 0.4 0.4

The above are some reference values for leaving nodes on common plate thicknesses, but the actual values depend on the specific situation. As for how many nodes are appropriate, generally, we should leave one node between every 350-400mm. For example, if there is a 50x1200mm rectangular unfolded diagram, we can divide it into three sections and leave two nodes in the middle. Try to leave nodes symmetrically on the product to maintain balanced stress.

Note: During the typesetting process, nodes should be appropriately added at certain points.


Place different products of the same material and plate thickness on a single sheet for one-time processing to achieve material, time, and effort savings.

  1. Familiarize yourself with material specifications:
  • Aluminum plate: t(thickness) * 1220 * 2440
  • Copper plate: t(thickness) * 600 * 1500
  • Cold plate (SPC): t(thickness) * 1250 * 2500 [t(thickness) * 1220 * 2440]
  • Pickled plate (SPHC/SPHD): t(thickness) * 1250 * 2500 [t(thickness) * 1220 * 2440]
  • Electrolytic plate: t(thickness) * 1220 * 2440
  • Stainless steel plate: t(thickness) * 1220 * 2440

These are some common sheet material specifications. Custom specifications can be ordered based on the unfolded product size requirements.

  1. Safety zone: Pay attention to the safety zone during typesetting. Generally, the D-station cutting edge is set to 1580, and the E-station cutting edge is set to 20110. Do not include the die within the safety zone to avoid damaging the die and clamp.
  2. Distance between layouts: During typesetting, the minimum distance between products should be no less than the die width. For example, using RE45*5 for cutting, the minimum distance should not be less than 5mm.
  3. Shared edge typesetting: AP100 has an automatic shared edge command, but it can also be done manually. When typesetting with shared edges, be sure to increase the size of the nodes or leave more.
  4. Die selection in typesetting: Use as few dies as possible in typesetting. In the punching sequence, the last cutting die should be punched from the opposite side of the clamp toward the clamp.
  5. Special forming die punching: For forming dies such as flanging, half-drawing, louver, and bridge pressing, pay special attention to the punching sequence. If forming downward, leave larger nodes and place the forming die last in the sequence, punching from the clamp toward the other side along the X direction and exiting outward. If forming upward, ensure that subsequent dies do not press the forming position, so it does not need to be placed last in the sequence.

Common Issues in Programming Typesetting

There are several common issues in programming typesetting:

  1. Embossing:

a) Material itself: For soft and light materials, such as aluminum plates, embossing can easily occur during the punching process. Due to the light weight of the aluminum plate, the cutting waste itself is very light at the same punching speed, and when the waste has not yet completely fallen off, it is lifted by the upper die, and embossing occurs when the waste is pressed onto the plate during the next cut.

b) Punching speed: During the cutting process, if the speed is too fast and the waste has not yet completely fallen off, the upper die lifts the waste, and embossing occurs when the waste is pressed onto the plate during the next cut.

c) Insufficient cutting amount: During the punching process, if the cutting amount is less than 2/3, the die may lift the waste.

  1. Dragging material:

a) Insufficient depth of the upper die: If the material is not completely punched through, the upper die is likely to drag the material when it lifts.

b) Unreasonable die clearance: If the lower die clearance is too small, it is easy to jam the material, and the plate is likely to drag the material during movement.

c) Die cutting edge not sharp: If the material is not completely punched through, the upper die is likely to drag the material when it lifts.

d) Press punching speed: If the speed is too fast and the material is not completely cut or dropped, it can cause the material to be dragged.

e) Insufficient ejection force: The spring pressure is not enough.

f) Misaligned punch, uneven force distribution.

  1. Residual die:

a) Insufficient cutting amount: When it is less than 2/3 of the die length, residual die may occur.

b) During erosion, if the pitch is too small, severe residual die is likely. Adjust the pitch appropriately according to actual requirements.

  1. Product falling off:

a) Nodes are too small, too few, or not placed reasonably.

  1. Half-drawing displacement and scratches:

When the plate moves, the half-drawing is scratched within the knife disc. When the half-drawing moves in the knife disc, it gets stuck in the lower die. When the plate moves, the half-drawing is forcibly dragged out, causing material displacement and leading to other half-drawings being displaced.

To avoid these issues, consider the factors causing these problems and take into account programming and on-site operation to solve problems more quickly and accurately.

How useful was this post?

Click on a star to rate it!

Average rating 0 / 5. Vote count: 0

No votes so far! Be the first to rate this post.

As you found this post useful...

Follow us on social media!

We are sorry that this post was not useful for you!

Let us improve this post!

Tell us how we can improve this post?

Just a Step Away!

Sheet Metal Machines Await!

Leave a Comment

Your email address will not be published. Required fields are marked *

Scroll to Top